Using the built-in Helpers

In this tutorial, we are going to use the Polar Coordinates Calculator, the Arc Calculator and the Corner tool. You find them all under Tools - Helpers in the menu.

image

This tutorial is made in millimeters. Open a milling machine and change the settings to millimeters if it is not already set.

Consider the drawing below. We have many dimensions on it, but not all positions are there. They have to be calculated. For example, we have no idea where the 69.469 distance angled line ends in the X axis and we also do not know where the center of R16.071 is located.

We could of course, draw the contour in SimCam and have it creating the CNC program for us, but there is an alternative method using the built-in helpers.

clip_image004

We are only going to focus on solving the unknown coordinates, in this exercise. If you would do this as a real project, you would need to add roughing cuts, as well as radius compensation (G41/ G42) and realistic feeds and speeds.

Start by adding a workpiece with the size X100, Y80 and Z25.

clip_image006

Click on the "Insert at cursor" button.

clip_image008

Let us now move the zero point of the program to X5, Y6.867 and Z25, to make it easier to create the program (the dimensions are drawn from that position). We also select a tool.

clip_image010

And then we add a couple of blocks, to position the tool and feed down to Z-5.

clip_image012

Now, let us have a look at the drawing again.

clip_image014

Our first position is easy, it is located at X0, Y25.517 according to the drawing. We add this to the program.

clip_image016

Now it's getting trickier. We don't know where the next position is. Let us use the Polar Coordinate Calculator.

clip_image018

 

First simulate the program you have so far. This will help us as the reference point will be filled out automatically from the current tool position.

Click on Tools - Helpers - Polar coords calculator or press Control - O on the keyboard.

The angle is 123.1 according to the drawing, but we measure the angle from straight to the right, so we will have to take 90 degrees off that value. We end up with 123.1 - 90 = 33.1 degrees.

clip_image020

The distance is 69.469 according to the drawing.

clip_image022

As you can see, the calculator creates the CNC block for us. Click on the "Insert at cursor" button to send it to the program.

Simulate the program again.

clip_image024

Great! Next, let us do the arc in the corner.

The corner tool can help us with all three blocks to go over the corner and end at the beginning of arc R16.071.

clip_image026

Click on Tools - Helpers - Corner fillet or chamfer.

As you can see from the hint picture in the dialog, we need to type in 3 points. The first one is already filled in for us as it is the current tool position. The second one is the position of the corner and then the end point.

image

The final position in Y, is not written on the drawing. But we can easily calculate it by taking 17.026 from our current position. We end up with 63.454 - 17.026 = 46.428.

We also type in the radius (10) and our blocks gets automatically created for us.

clip_image028

Again, click the "Insert at cursor" button.

Simulate the program.

clip_image030

clip_image032

Now it is time to deal with the arc (R16.071) on the right side. From the drawing, we see that we know its endpoint but we do not have any information about its center. Let us use the Arc Calculator to solve that problem.

clip_image004

Click Tools - Helpers - Arc Calculator (or press Control - R on the keyboard).

The start point has already been filled out for us. Enter the end point and the radius and put the switch on Anti clockwise direction.


clip_image034

Again, click "Insert at cursor".

Now, add the remaining blocks to go back to the start of the contour.

clip_image036 

clip_image038

Good work!

We hope that this tutorial has shown you how easy it is to solve geometrical problems using the Helpers.