CNCSimulator Pro

user guide
Index Tutorial 1 Milling

Important note: This tutorial was written prior to version 2.5. Earlier versions did not have CAD drawing lines, arcs and circles. Because of this we are only using basic guide lines and circles here. For updated tutorials, look under the topic "Version 2.5 and later".
Welcome to this SimCam tutorial where we are going to make a canon wheel. Our goal is not to teach you all about the program but rather to get you started with some basic concepts of SimCam.
Here is a video of the steps in the tutorial. Use it as a companion (pause and play as needed) during the tutorial.
The tutorial is made for millimeters. First go to the Program Settings by selecting Settings - Settings  and choose the Program tab. Select Use millimeters and click on the OK button. Then load the machine by clicking this button   and select the Milling Center machine. Do not forget to uncheck the Open demo checkbox.
The next thing we have to do is make sure we have a workpiece matching the drawing in our workpiece registry.
Click SettingsInventory Browser (F2) in the main menu and select the Mill Workpieces tab.
Now, click on the green plus button in the upper right corner to add a new workpiece (only if you do not already have a workpiece with these measurements of course.)
Enter X100, Y100 and Z20 and type in a name for the workpiece, then click OK.
Click on the SimCam tab to switch over to the SimCam view, then click [More] – [Workpiece] from the SimCam menu.
Select the workpiece you created (or already had).
Tips! Always start a new project by adding a workpiece.
You should now see a blue rectangle representing the workpiece on screen. With the mouse wheel, you can zoom out to a screen size you like.
SimCam uses so called Guides Lines and Circles to define the geometry. As you can see, four guide lines have already been added for you. SimCam has also added some useful points.
We will start by drawing the radius 45 circle at the center of the workpiece.
From the SimCam menu, click [Circle] – [Center – Radius].
Move the mouse to the center of the workpiece and see how it snaps to the center point automatically added for us. Click when the mouse has locked to the center.
Drag the mouse until you read 45 for its radius and make another click.
OK, we have the outer contour for the wheel. Let's add guide lines to help us define one of the wedge pockets.
From the SimCam menu, click [Line].
Click the center and the right extreme point of the circle. The mouse hair cross will snap automatically to these points.
A horizontal guide line will be added to the drawing.
Now, let's draw a line from the center and out in a 45 degrees angle. We could of course just draw the line from the center of the circle to the upper right corner of the workpiece, but we want to teach you a technique for drawing lines using polar coordinates.
Again, click [Line] in the menu and click the center of the circle for starting point. Then click [Enter angle] in the menu to show the angle input field.
You can now either enter the angle (45) in the input field and click OK or move the mouse and make a click when you read angle 45 at the angle gauge.
This is what you should have now. And that is actually all guides we need to make our entire canon wheel!
Now it is time to add a contour for making one of the wedge pockets.
From the SimCam menu, click [More] – [Contour].
Click the center of the circle.
Now you will see “the Tracker”. He will follow your steps until you are done with the contour. To show the tracker where to go, click on as many snap points along the way as possible.
Click the intersection between the horizontal line and the circle. Continue by clicking the intersection point between the 45 degrees line and the circle and end by clicking the center of the circle again. Finally, click on [Done] in the SimCam menu.
Now your contour should look like this:
Information: Note the big arrows showing the toolpath direction of the contour and the small arrows showing the so called toolside. The toolside can be either left, right or on contour. If you click on the contour, a menu will be shown allowing the user to change toolside and contour direction.
There is no need to change anything on this contour as the default toolside already is on the inside.
It is time to set the parameters for the contour layer.
Click on the button at the lower left corner to show the layers dialog.
As you can see, two layers have been automatically created for us. One guide layer and one contour layer.
At any time you can show/ hide and enable/ disable a layer. Each contour layer has a gear button to open its parameters.
On the contour layer, click the gear button.
The Cutting Operation Parameters dialog will be shown.
At the top, enter the name of the operation and select operation type. We will use this contour to pocket mill the inside.
For the moment, we can leave all other parameters as is. Click OK to close the dialog.
As you can see, the pocket cuts have been automatically calculated for us, and a CNC program is already produced!
Well, let's get back to the parameters and set some more data for the pocket to be as we want it.
Click on the gear button again on the contour layer.
Enter 2 for Save for fine cut and 10 for Cutting Depth.
Let's say our machine or tool does not allow us to cut the whole depth at once. To solve this, click on the Stepping tab and check Use Stepping.
Fill out the values from the image.
Now, click OK to close the parameters dialog and note how the program and drawing has changed.
At this point, we can check the CNC program by clicking the play button.
The view will automatically change to the 3D view and simulation will start.
Click on the SimCam tab to get back to the SimCam view.
Now we are going to add seven rotated copies of the layer to make all pockets.
In the layers dialog, click on the contour layer to select it.
A selected layer gets a dark gray background.
Now, at the bottom of the dialog, click on the Duplicate Layer button.
You will get an identical copy of your contour layer. Click on its gear button to open the parameters for the new layer.
Click on the Transformation tab to see the transformation settings.
Under rotate fill in 45 for angle and 70, 70 for X and Y rotation center.
Click on OK. Now you should have a rotated copy looking like this:
Now for the magic, as the second copy has a rotation transformation, all copies from now on will get rotated 45 degrees. Click six times on the Duplicate layer button and see for yourself!
This is what you should have now:
If you want, click on the play button now to simulate what we got so far. Also, it might be a good idea to save your work at this time. Do this by selecting FileSave SimCam file from the main menu.
Now it is time to add a contour for the outside pocket operation (please note that we call all operations pocket operations even if we are not talking about an actual pocket with outer borders).
So, to take away the material outside of the circle, we need to define the outer contour of the workpiece as a pocket with the circle as an island (to be left untouched).
First of all, let's hide all pocket layers while we do our final work. Click on the bulb button at the bottom of the layers dialog and select Hide All to hide all layers.
Show the guide layer by clicking the Eye button.
From the SimCam menu, click [More] – [Contour].
Click all four corners of the workpiece rectangle in a clockwise order starting with the lower left corner.  End by clicking the first corner point again and then on [Done] in the SimCam menu.
Important information! Every time we create a new contour a new contour layer will be added for us if a guide layer is the selected layer. The selected layer has a dark gray background. As we are going to make a pocket with an island, we need more than one contour on the same layer and hence we need to make the contour layer the selected one to avoid automatic creation of a new layer.
In the layers dialog, click the contour layer we just created to select it.
Now we can define the second contour that will end up on the same layer.
From the SimCam menu, click [More] – [Contour].
Click on the left extreme point on the circle (the point most to the left, there will be a snap point there).
Click on the upper extreme point, then to right one, the bottom one and finally on the left one again to close the contour.
Now your drawing should look like this:
This final layer contains two contours. The second (and following) contour(s) will automatically be treated as islands when we make it a pocket layer.
As you can see from the circle contour, there are small arrows pointing outwards from the contour.  That is good as we want the tool to stay on the outside of the circular island. But the square contour defining the outside of the pocket operation also has outwards arrows. Let us correct that by changing the toolside of that contour.
To be able to click on a contour, we have to disable the guide layer to avoid confusion with the guide lines and circles.
At the top layer, the guide layer, click on the Padlock to deactivate it.
Now, click on the outer rectangular contour and click on [Flip toolside] once so that the arrows disappear.
The final step is to open up the parameters for the new layer and make it a pocket layer. Also fill out the cutting data as shown.
If you want, activate stepping on this layer as well, just like we did before with the wedge pocket.
Click OK when ready.
Click on the bulb button to show all layers.
This is how your part should look like now:
Now, click on the play button.
Congratulations, you have just finished your first SimCam tutorial!